ENGIN GRAPHICS & 3-D MODELING

FEATURES

ENGR 248 – Lab 5

Learning Outcomes

◦ Learn how to find and apply advanced features in SolidWorks

◦ Learn how to create renders

◦ Learn how to generate drawing in SolidWorks

REQUIREMENTS

Requirements

◦ Create the Tea Plop

◦ It is highly recommend you do this all within your lab time so you can receive help from TAs

◦ Submit a PDF in landscape

◦ Every page must have NAME, DATA, PAGE #, and “Sketching and SolidWorks Lab” on the

bottom

◦ SolidWorks models should be in a folder named Lastname_Lab5

◦ Submit a zipped version of Lastname_Lab5 and a PDF

Tips

◦ Save often

◦ Make sure files are backed up

◦ Give yourself extra time to submit the files incase something goes wrong

◦ Use PowerPoint to make your PDF for submission

SUBMISSION CONTENTS

Content to Submit

◦ Lastname_Lab#_ENGR248.pdf

◦ Title page: Name, ENGR 248, Due Date, Lab Number, number of pages

◦ Includes hand drawings

◦ Should have page numbers on each page

◦ Pages should have NAME, DATA, PAGE #, and “Sketching and SolidWorks Lab” on the bottom

◦ Lastname_Lab#_ENGR248_SLD.zip

◦ Contains all of your SolidWorks models

Content to Submit

Lab Excercise Require Materials Number of Pages

SolidWorks ZIP PDF

Title Page Title Content 1

The Tea Plop Render Rendered Image 1

Dimensioned SW

Drawing

PDF page 1

Part File SLDPRT

Drawing File SLDDRW

ATTENDANCE ASSIGNMENT

Attendance Assignment

◦ THERE IS NONE THIS WEEK!

◦ You will need the entire lab time to complete your lab

FEATURES TO ADD

MAKE A CUBE Start by creating a 30 cm

cube, like we did in the

last lab

First and Last Name Create a sketch on the

front face of the cube

and add then use the

sketch text tool to add

YOUR OWN FIRST AND

LAST NAME as shown

Extrude it Extrude your name out by

1 cm

Add the handle Create this sketch on the

right side of the cube

Add the handle Perform a 135 degree

blind revolve (you may

need to flip its direction)

The hole in top Create a sketch on the

top face of the cube and

use offset entities to

create a square that is 5

cm within the board of

the face

The hole in top It should look like this after

you hit the green

checkmark

Insert planes Use the reference

geometry tools in the

Features tab to insert a

plane that is 5 cm from

the top face

Insert planes Create a second plane

that is 5cm off of the first

plane

Create a sketch on plane 1

Create a sketch on plane 1 Draw this in the sketch on

plane 1

Create a sketch on plane 2

Create a sketch on plane 2 Create this sketch on

plane 2

Create a lofted shape Use Lofted Boss/Base from

the features tab to create

the lofted shape

Select the sketch on the

top face first, and then

the sketch on plane 1,

and select the sketch on

plane 2 last

Check your work It should look like this

Create a sketch on the left face

Create a sketch on the left face Create the sketch shown

on the left face and then

close the sketch

Add a plane Use the center line you

created in the last sketch

to create a plane parallel

to the front pace

Sketch on the plane Create the sketch shown on the plane, make sure that you have all of your relations.

I used two 3 point arcs starting from the center of the circle.

The first arc has its center at the midpoint of a construction line going from the top to the bottom of the tea plop face and its end point is horizontal with that point

Create a sweep Use Swept Boss/Base to

make the spout

You need to select the

circle as the face and the

two arcs as the path

Check your work Also, remember to save

Dome the end of the spout Go to the insert

dropdown along the top

Select Features

Select dome

Do a 6 cm dome on the

end of the spout

Check your work

Chamfer the edges along the top face Select the dropdown

arrow below filet and

select chamfer

Add a chamfer to the

four edges of the top

face

Create a sketch on the bottom face

Create a sketch on the bottom face Draw this sketch

Extrude the sketch Extrude the sketch by 2

cm

Edit the sketch Go back and edit the

sketch the make 4

squares using a linear

pattern

Check your work Remember to save

Draft the feet Add a 5 degree draft to

all four sides of the feet

Draft the feet Make sure you got all four

sides

Check your draft The feet should now be

slightly tapered

Add a fillet In the feature tab, add a

2 cm fillet to the base of

the handle

Attempt to shell out the tea plop Click the top face of the

top plop, then click shell

Attempt to add a 3 cm

shell

If you get an error

message proceed to the

next slide

Just go with it Click ok and wait and see

what breaks

Look at what broke Both the letters on the

name and the handle

are too small to be

shelled out

Hit the red x the reject the

shelling

Suppress the features Right-click the text (boss-

extrude 2 probably) and

select suppress

http://blog.dasisolutions.com/wp-content/uploads/2012/05/SuppressPartIcon.png

Drag the features to the bottom First drag the revolve to

the bottom of the tree, it

should be just above the

fillet

Next drag the extrusion of

the text to just above the

revolve

Finally grab the little blue

bar at the bottom and

drag it to above these

three features as shown

Shell the tea plop Add a 3 cm shell to the

teapots top face

Just go with it If you get the error again

hit ok, this time every

thing should go through

Check your work Remember to save your

work

Unsuppress the features Drag the blue bar back

to the bottom

Right click the revolve

and the extrude and click

the suppress icon again

to unsuppress them

Create a sketch on the front plane

Create a sketch on the front plane Draw an ellipse with the

dimensions and relations

shown

Cut out the ellipse Use Extruded-Cut to cut

the ellipse

Set the distance to

through all

Check your work Here is a little tea plop (it

would make a very poor

tea pot)

Remember to save your

work

MATERIAL AND RENDERING

Edit the appearance Click edit appearance

Select an appearance material Select an appearance

material of your choice,

make sure that your

name will still be visible

with the selected material

Turn on PhotoView 360 In SolidWorks Add-Ins turn

on PhotoView 360

Render Tools You should now have the

render tools tab

Select Render Region Click render region and

adjust the region to show

the entire object, but not

much more

Final Render Click final render

Select turn on Perspective

view

The Final Render Window You should get a final

render window with an

image slowly being

rendered

The Final Render Window Be patient

If you want a background

in your render, you can

select one using the

apply scene option THIS IS

NOT REQUIRED

Save your render

Check your work You will need to include

your final render in the

PDF for this lab

DRAWING

Create a drawing from the part In the part file click file,

make drawing from part

Select an A2 sheet

Drag in the front view Click and drag in the

from the view palette

After you drop it in you

can drag around your

mouse and it will give you

the top side and

perspective view

Create a drawing from the part After you drop it in you

can drag around your

mouse and it will give you

the top side and

perspective view

Adjust your spacing Drag around your view to

space them out better on

the page

Add dimensions Using smart dimension

add the dimensions

shown

Save your work as a PDF Save the drawing and

then save it again but

instead save it as a pdf

Check your work Open the PDF of your drawing, double check that

is has the correct filename format in drawing number

(it should be Lastname_Lab6)

If the file name is wrong you

will have to resave the part as the appropriate name

first and the update it in the drawing or create a new

drawing

Merge this with a PDF including a title page, and

your render